To Draw a Bottle by Using 3D Sketch & Lofted Boss - Part 1

This model use 3D Sketch and Lofted Boss. You will learn how to draw by 3D sketch, convert line to construction line, lofted boss using profiles and guide lines, and others tips.

Please try by follow this tutorial ( I use SolidWorks 2007 to make this tutorial) : I. Creating 2D Sketch for Base of Bottle 1. Open a new part, and in the Feature Manager design tree, select the Top plane.

2. Click Rectangle on the Sketch toolbar, and create a rectangle by the origin inside of rectangle.

3. Click Smart Dimension (Dimensions/Relations toolbar), and fully defined the sketch. 4. Click Offset Entities on the Sketch toolbar. 5. In the Property Manager, under Parameters:

• Set Offset Distance to 1.

• Select Add dimensions, Reverse, and Select chain

In the graphics area select the entities, then click OK 6. Select all entities in the graphics area by left click and drag a rectangular as shown below. 7. In the Property Manager, under Option:

• Select For construction.

8. Click OK 9. Click 3 Point Arc on the Sketch toolbar.

10. On the one of inside entities, select start and end points, then drag the arc on the mid one of outside entities to set the radius.

11. Click OK 12. Click Fillet on the Sketch toolbar. 13. In the Property Manager, under Fillet Parameters:

• Set Radius to 5.

In the graphics area select the two arcs. 14. Click OK , then Click Exit Sketch II. Creating 3D Sketch to Define Top and Side of Bottle 1. Click Isometric on the Standard Views toolbar. 2. In the Feature Manager design tree, select the Top plane. 3. Click Plane on the Sketch toolbar. 4. In the Property Manager, under First Reference:

• Set Distance to 44.

5. Click OK . 6. Click Circle on the Sketch toolbar.

7. Sketch a circle on Plane 2, with the center approximately along the same vertical axis as the sketch origin.

8. Click Add Relation on the Dimensions/Relations toolbar.

9. In the graphics area select the arc and the origin

10. In the PropertyManager, under Add Relations click Concentric , then click OK .

11. Click Smart Dimension on the Dimensions/Relations toolbar, and dimension the arc diameter to 21.

III. Creating the First Splines 1. Click Plane on the Sketch toolbar. 2. In the FeatureManager design tree, select Front for First Reference. 3. In the PropertyManager, under First Reference:

• Click Coincident , then click OK .

4. Click Spline on the Sketch toolbar. 5. Sketch a two point spline coincident with the ends points of the tangent arc. 6. Repeat step 5 with the points shown. 7. Click Normal To on the Standard Views Toolbar. 8. Select one of the two entities on the graphic area. 9. Click the dot on head arrow and drag until became a curve. 10. In the Property Manager, under Parameters:

• Set Tangent Weighting 1 to 60.

• Set Tangent Radial Direction to -100.

11. Repeat step 8-9 with the other entity. 12. In the Property Manager, under Parameters:

• Set Tangent Weighting 1 to 60.

• Set Tangent Radial Direction to -80.

13. Click OK . IV. Creating the Second Splines 1. Click Isometric on the Standard Views toolbar. 2. Click Plane on the Sketch toolbar. 3. In the FeatureManager design tree, select Right for First Reference. 4. In the PropertyManager, under First Reference:

• Click Coincident , then click OK .

5. Click Spline on the Sketch toolbar. 6. Sketch a two point spline coincident with the ends points of the tangent arc. 7. Repeat step 6 with the points shown. 8. Click Normal To on the Standard Views Toolbar. 9. Select one of the two entities on the graphic area. 10. Click the dot on head arrow and drag until became a curve. 11. In the Property Manager, under Parameters:

• Set Tangent Weighting 1 to 55.
• Set Tangent Polar Direction to -10.

12. Repeat step 9 - 10 with the other entity. 13. In the Property Manager, under Parameters:

• Set Tangent Weighting 1 to 55.

• Set Tangent Polar Direction to -10.

14. Click OK , then Click Exit Sketch . V. Creating Bottle by Lofted Boss 1. Click Isometric on the Standard Views toolbar. 2. Click Lofted Boss on the Feature Toolbar. 3. Right-click in the graphics area and choose SelectionManager. 4. In the SelectionManager, click Select Closed Loop . 5. Select the Sketch1 for Profiles and click . 6. Select and accept the circular sketch for Profiles . 7. In the PropertyManager, click in Guide Curves. 8. In the graphics area, right-click and choose SelectionManager. Use the Select Open Loop tool to select the four splines for Guide Curves . 9. Click OK . 10. Click Fillet on the Feature Toolbar. 11. In the Property Manager, under Item To Fillet:

• Set Radius to 1.5.
• Select Edge<1> of Loft in Edges, Faces, Features and Loops

12. Click OK . Congratulations! You have completed this lesson. For more detail, please see on video tutorial below: * For better playback, allow the video to download before playing Download WMV ( 5.1 MB compressed file )